Answers › Bosses and ribs

Bosses and ribs in molded parts

Bosses host your screws, inserts and pins; ribs add stiffness without thickening the wall. Both are just local thick spots, and thick spots are where molded parts go wrong — sink on the show face, warp, short fill, a boss that splits. The whole craft is adding the strength you need while keeping the feature thin enough not to leave a mark. Here are the representative rules and the traps, from the floor.

A dimensioned part drawing with calipers resting on a workbench, the stage where boss and rib sizing is decided.
Boss and rib sizing is settled on the drawing — a caliper and the fastener data sheet — long before steel is cut. Fix a thick junction here and it costs nothing.

What a rib actually buys you

The reason ribs exist is that stiffness is cheap to buy with height and expensive to buy with wall. A flat panel's bending stiffness rises with roughly the cube of its depth, so standing a thin rib up off the surface adds far more resistance to bending than adding the same material back into the wall as thickness. Put plainly: a short rib can do what a noticeably thicker wall would do, for a fraction of the extra plastic — and without the slow cooling, the sink and the warp that a thick wall drags in with it. That is the trade at the heart of good molded-part design. When a part feels flimsy, the instinct is to thicken the wall; the better move is almost always to leave the wall thin and uniform and add ribs where the load is. A grid of shallow ribs under a cover, a pair of ribs bracing a mounting face, a rib running the length of a panel that wants to oil-can — all of them stiffen the part while keeping every wall at its nominal thickness so the part still cools evenly and ejects clean.

Rib design rules (representative)

Ribs reward restraint. The numbers below are typical starting points for common thermoplastics, not fixed laws — your resin, wall and cosmetic requirements shift them, and a filled grade behaves differently from an unfilled one. The rib and boss ratios on this page are the standard public design-for-manufacture guidance published in Protolabs' injection-molding design guidelines and in the Covestro (formerly Bayer) Part and Mold Design guide for engineering thermoplastics; they are rules of thumb, not JCH-specific specifications.

Ribbed-wall cross-sectionCross-section of a ribbed wall: nominal wall, a rib about 0.4 to 0.6 times the wall thickness at its base, a base radius, draft, and a shallow sink mark on the opposite show face. nominal wall (t) rib base ≈ 0.4–0.6 t base radius draft 0.5–1°/side show face — sink if rib too thick height ≤ ~3 t

What a boss does — and its rules

A boss is a raised cylinder, usually with a hole, that gives the part somewhere to take a fastener: a self-tapping screw, a threaded insert, or a locating pin for assembly. The problem is identical to the rib — it is a lump of extra material — so the rules rhyme. Representative guidance:

Picture the difference: a lone fat post sticking up off a thin floor is a sink and a crack waiting to happen; a cored cylinder at ~60% wall, braced by two thin gussets to the sidewall, with a small base fillet, carries a screw all day and leaves the show face flat.

Boss and rib design rulesA rule tree of typical DFM guidance for bosses and ribs: ribs sized to 40-60% of the adjoining wall, height up to about 3x the wall, 0.5-1 degree draft per side and a small base radius; bosses with an outside diameter about twice the screw or hole, wall about 60% of nominal, cored rather than solid, gusseted when tall, and radiused at the base to reduce stress.Ribs for stiffnessBosses for fasteners

Boss and rib DFM rules

Rib

Boss

Base thickness 40-60% of wall - avoid sink

Height up to about 3x wall

Draft 0.5-1 deg per side

Small radius at base

OD about 2x screw or hole dia

Wall about 60% of nominal

Core it - never mold solid

Gusset a tall boss

Radius at base to cut stress

Typical DFM guidance for bosses and ribs as a rule tree. Ribs branch to thickness, height, draft and base-radius rules; bosses branch to outside diameter, wall, coring, gusseting and base-radius rules. Representative starting points for common thermoplastics, not fixed laws or JCH-specific specs.

The sink-mark trap

This is the mistake we see most, so it earns its own section. When a boss or rib is sinking the opposite face, the tempting fix is to feel like the part is "too thin there" and add wall. That is backwards. The sink is caused by too much material at the junction, not too little: the thick root stays molten and shrinking after the surrounding skin has frozen, and it drags that frozen show surface inward. Adding wall adds mass, cools even slower, and deepens the sink while inviting warp. The correct move is to remove mass — thin the rib or boss root toward half the wall, core a solid boss, and trim an over-large base fillet. If a faint sink remains on a visible face after the geometry is right, a texture on that face hides it far better than a smooth gloss, and gate placement can help; but geometry is the lever that actually works. (More on the mechanism in sink marks in injection molding, and on why uniform walls matter in how wall thickness affects a molded part.)

Boss for a self-tapping screw vs a heat-set or ultrasonic insert

The boss geometry is similar; the hole is not, and this is where parts get stripped. A self-tapping, thread-forming screw needs a pilot hole slightly smaller than the screw so the thread rolls or cuts into the plastic as it drives — too big and it strips, too small and the boss splits on the first drive. A heat-set or ultrasonic insert is the opposite philosophy: the metal insert is melted into a hole sized to its lead-in diameter, and once seated it provides the real metal thread for repeated assembly and disassembly. Inserts are the right call where a joint will be opened and closed many times, or carries real torque; self-tappers suit low-cost, assemble-once joints. In both cases the fastener or insert supplier publishes the recommended boss hole and outside diameter for each size and resin — that published number is the one to use, varying by whether the resin is unfilled, filled or a softer grade. Design the boss around the fastener data sheet, not a generic number, and the joint holds.

Self-tapping screw bossHeat-set / ultrasonic insert boss
HolePilot slightly smaller than screw (thread forms into plastic)Sized to insert lead-in diameter (insert melts in)
ThreadFormed in the plastic itselfMetal insert carries the thread
Best forLow-cost, assemble-once jointsRepeated assembly, higher torque
Size fromScrew maker's boss spec for your resinInsert maker's hole spec for your resin

Gating and knit-line notes

Where the plastic enters and how it flows past these features matters as much as their proportions. Ribs and bosses fill last because they are deep and narrow, so a gate placed to drive flow toward them, rather than leaving them at the dead end of a long flow path, fills them fully and packs out their roots to fight sink. Tall ribs and deep bosses need a vent at the far point or they trap gas, burn and short-fill at the tip. And wherever flow splits around a boss or a hole and rejoins on the far side, it forms a knit line (weld line) — a seam that is cosmetically visible and mechanically weaker than solid material. Keep that knit line away from the spot that takes load, such as directly under a screw head, or expect the boss to be weaker there than the math suggests. (See weld lines and knit lines for how these form and how to place them.)

Do and avoid: a quick reference

The same mistake runs through almost every boss and rib problem: too much mass at the junction. This table pairs the move that works with the move that sinks, warps or splits the part. The ratios are representative public DFM guidance for common thermoplastics (see the Protolabs and Covestro/Bayer references cited above), not fixed numbers for your resin.

Boss and rib design: do vs avoid, with the reason each rule exists. Qualitative ratios only — representative DFM rules of thumb, not prices, not certifications, and not part-specific specifications.
FeatureDoAvoidWhy
Rib base thicknessRoughly 40–60% of the adjoining nominal wallMolding the rib at full wall thicknessA full-thickness junction is extra mass that cools slowly and pulls a sink on the show face opposite the rib
Rib heightUp to about 3× the nominal wall; use several short ribs for more stiffnessOne very tall rib far above 3× the wallTall, deep ribs are hard to fill, hard to vent at the tip and hard to eject
Boss wallAbout 60% of the nominal wall, cored down the middleA solid or full-thickness bossA solid slug cools unevenly, sinks the root and can void inside
Boss outside diameterAbout 2× the screw or hole diameterA thin wall of plastic around the fastenerToo little wall splits under torque and pull-out; too much rebuilds a thick junction that sinks
Base radiusA small fillet where the feature meets the wallA sharp inside corner — or an over-large radiusA sharp corner is a stress riser and flow restriction; a large radius rebuilds the mass that causes sink
DraftRoughly 0.5–1° per side (a heavier texture needs more)Zero draft on a deep rib or bossA deep, narrow feature with no draft drags on the steel, scuffs and ejects poorly

What to flag to your molder

Before steel is cut, hand the molder the nominal wall thickness, the resin and grade, the specific screw or insert part number for every boss, the load each boss has to carry, and a clear marking of which faces are cosmetic. Ask for a moldability or DFM review and, on the features that matter, a short mold-flow look at fill, knit-line location and sink around the bosses and ribs. A ribbed, bossed part that passes that review on the model is cheap to adjust; the same part discovered to sink, strip or short-fill after the tool is machined is not. If you want a second set of eyes before committing, the plastics material selector helps pin down the grade, and we are happy to look at the part itself.

Common questions

How thick should a rib be? Thinner than the wall it stands on — see the rib rules and the do-vs-avoid table above for the base-thickness, height and draft ranges. The point is to keep the junction light so it doesn't sink the opposite show face.

What are the boss rules? Same idea as a rib: keep the cylinder thin and feedable, core it rather than molding it solid, give it enough wall around the fastener, and brace a tall one with a gusset. The full boss ranges are in the boss rules and comparison table above.

Why is my part sinking opposite a rib or boss? Too much mass at the junction, not too little. Thin the feature and core the boss — don't add wall, which deepens the sink.

Self-tapping screw or insert? Self-tappers for assemble-once, low-cost joints; heat-set or ultrasonic inserts for repeated assembly and higher torque. The hole size differs — take it from the fastener maker's data for your resin.

What causes a weak boss? A knit line under the load, a thin or split wall from the wrong hole size, or an unbraced boss. Place the knit line away from the screw and size the hole from the supplier spec.

Engineering estimate, not a quote. The thicknesses, heights, ratios and angles here are representative rules of thumb for common thermoplastics; the right values for your part depend on the resin, wall, loads and cosmetics, and should be confirmed with the fastener maker's data and a moldability review.

JCH Design & Manufacturing can review your bosses and ribs against your resin, your fasteners and your cosmetic faces — before the tool is cut — and tell you where a feature will sink, warp, short-fill or split, and how to fix it. Send your part and the screws or inserts you plan to use; NDA first.

Book a 30-minute call