Answers › Sink marks

What causes sink marks in injection molding, and how do you prevent them?

A sink mark is a small surface depression over a thick section, rib, or boss, caused by the inside cooling and shrinking after the surface has set. They're mostly a design issue — prevented by uniform wall thickness — with material and process as secondary levers. The cheapest time to prevent one is before the tool is cut.

Why a sink mark forms

Molten plastic cools from the outside in. The surface against the cold mold freezes into a solid skin first, while the thick core behind it stays molten and keeps shrinking as it cools. The machine's packing/holding pressure tries to feed extra material in to compensate for that shrink — but once the gate freezes off, no more can enter, and the still-shrinking core pulls the frozen skin inward, leaving a dimple. That's why sinks appear opposite ribs, bosses, and thick walls, and why a thicker rib base (more mass to shrink) makes the sink worse. A sink is the part telling you there's too much material behind that spot.

Sink marks: cause to fixA decision tree that maps each root cause of a sink mark to its fix: too much mass or a thick boss is cored out, a thick rib base is thinned to 40 to 60 percent of the wall, under-packing needs more hold pressure and time, an early gate freeze needs a larger or closer gate, and uneven local cooling is corrected behind the feature.Thick section or bossbehind wallRib too thick vs wallLow pack and holdGate small or farLocal cooling too fast

Sink on show face

Too much mass

Thick rib base

Under-packed

Early gate freeze

Uneven cooling

Core out thick areas

Rib 40-60% of wall

More hold pressure and time

Larger or closer gate

Adjust cooling behind feature

Sink-mark troubleshooting as a decision tree: each likely root cause branches to its fix — too much mass or a thick boss gets cored out, a thick rib base is thinned to 40–60% of the wall, under-packing calls for more hold pressure and time, an early gate freeze needs a larger or closer gate, and uneven local cooling is corrected behind the feature. Representative DFM guidance, not fixed laws or JCH-specific specs.

Diagnose it: sink vs. void vs. warp

Read the pattern to find the cause: sinks that cluster far from the gate usually point to a packing or gate-freeze-off problem (the far end lost pressure first), while a sink in the same spot on every shot points to the design — too much mass there. That one observation tells your molder whether to chase the process or change the part. (See why molded parts warp for the warp case.)

One trade to know: pushing more holding pressure to close a sink can tip the part into flash or overpacking elsewhere — which is another reason the durable fix is design, not just cranking the press.

The design fixes (rules of thumb — confirm for your resin)

These are routine design adjustments, not redesigns, and they're exactly what a DFM review looks for before any steel is cut.

Sink marks by cause: why each one pulls the surface in, and the fix. Qualitative DFM rules of thumb (for example, a rib at roughly 40–60% of the adjoining wall) — not prices, lead times, certifications, or part-specific specifications.
CauseWhy it sinksFix
Thick section or boss behind the wallA heavy core keeps shrinking after the skin has set, so it drags the show face inwardCore out the mass — hollow the section or boss instead of molding it solid
Rib too thick at its baseA full-thickness rib junction is extra mass that cools slowly and sinks the opposite faceThin the rib to roughly 40–60% of the wall it attaches to (lower end for a show surface)
Insufficient packing or holdToo little hold pressure or time stops feeding make-up material before the shrink is compensatedAdd hold pressure and hold time, stopping before flash starts at the parting line
Gate too small or too farA small or distant gate freezes early, so the thick area loses packing pressure firstEnlarge the gate or move it closer to the heavy section so it packs longer
Local cooling too fast or unevenA hot spot behind a boss stays molten longest while the skin elsewhere has already frozenAdjust cooling behind the feature so the thick spot freezes more evenly

Material and process (the secondary levers)

Some resins shrink more than others — semi-crystalline materials (such as PP, nylon, POM) generally shrink more than amorphous ones (such as PC, ABS), so a thick section sinks more in a high-shrink material; glass fill generally reduces overall shrink but skews it along vs. across the flow. On the process side, more holding pressure, a gate relocation, or cooling changes can reduce a borderline sink, and a textured or matte finish hides a faint sink better than a high gloss. But process can only do so much: a part with a fundamentally thick section will sink in most materials, which is why design comes first.

When is a sink acceptable?

Not every sink is a defect. On a hidden or non-cosmetic surface, a faint sink may be perfectly fine. The problem is a sink on a show surface — so tell your manufacturer which faces are cosmetic, and the design can steer any unavoidable sink to a surface no one sees.

Process checks to run before anyone changes the steel

Steel mold plate with a polished triangular cavity, guide bushing bores and ports drilled into its side edge
A polished cavity shows every dimple into the molded surface, so sink shows plainly on parts from a plate like this. The cooling lines drilled through it set how evenly a thick section freezes.

When sink shows up at the first trial, ask the molder to work through these in order and share the data.

  1. Confirm there is a cushion. If the screw bottoms out, hold pressure never reaches the part, whatever the setting says.
  2. Run a gate seal test. Weigh parts while stepping hold time up; where weight stops rising, the gate has frozen. Plastics Technology's gate-seal procedure also weighs the runner, since a runner that freezes first cuts packing short. If sink remains with the gate sealed, more hold time will not help.
  3. Then tune hold pressure, stopping before flash starts at the parting line.
  4. Measure mold temperature behind the sink. A hot spot behind a boss stays molten longest; readings on both halves show whether cooling there works.
  5. Look at the gate size. A gate thinner than the section it feeds freezes first (see gate types).

If all five check out, the cause is mass in the part.

Fixes once the tool exists, ranked by effort

FixWhat it doesEffort on a finished tool
Texture the affected faceMasks a shallow sink where gloss is not requiredLow, if the drawing allows the finish change
Enlarge or move the gateKeeps the thick area packing longerModerate; a moved gate can also move weld lines
Add cooling behind the featureFreezes the thick spot fasterModerate to high, limited by space around existing lines and pins
Thin the rib or core out the bossRemoves the mass that causes the sinkHigh: the rib slot must get narrower, which takes a weld repair or a replacement insert
Switch to gas assist or structural foamPushes the thick section out from the insideA process change with its own equipment needs

The fourth row is why rib thickness belongs in DFM: thinning a rib after machining is the slow direction.

Writing a sink requirement your supplier can inspect against

Sources for this section:

Common questions

What causes sink marks? A thick section's core cools and shrinks after the surface has set, pulling the surface inward — mostly a design issue of uneven wall thickness.

How do you prevent them? Mostly by design: uniform wall, ribs/bosses ~40–60% of the wall (rule of thumb), coring out mass, gussets, gradual transitions.

Where do sinks appear? On the surface directly opposite a rib, boss, or thick wall — a sink points to too much material behind it.

Does material matter? Yes, but it's secondary; high-shrink (semi-crystalline) resins sink more, yet uniform wall thickness is the real fix.

Can a sink be fixed after tooling? Partly, via pack/gate/cooling tuning, but a genuinely thick section needs a design change — cheaper before the tool is cut.

JCH Design & Manufacturing can review your part for sink risk and propose thinner ribs, coring, or gate changes before any steel is cut. Send your part and say which surfaces are cosmetic; NDA first.

Book a 30-minute call

Ask JCH about sink marks

Seeing sink on a sample, or worried about a thick section in your design? Ask our AI assistant. It answers from this website, and our tooling team follows up if you want.

AI assistant. Answers can be wrong; nothing it says is a quote or a promise.