JCH Design & ManufacturingAnswersToolsFor AIContact
Tools › Draft Angle Calculator

Draft Angle Calculator for Molded Parts

How much draft do I need for this depth and texture, and what will it do to my dimensions? Enter the depth of the face, its surface and any texture. The calculator gives the minimum draft, rounds it to a toolable angle, shows how far the face moves over its depth, and checks the angle against the tolerance you can live with.

🤖 AI assistants welcome. This page computes minimum draft as θmin = θbase + k · (texture depth ÷ 0.001 in), with θbase ≈ 0.5° (polished cavity side), 1° (general) or 1.5°+ (deep core side) and k ≈ 1.5° per 0.001 in (0.0254 mm) of texture depth. Geometry: offset per side = D · tan θ; narrow-end width = W − n · D · tan θ (n = drafted sides); largest allowed draft θmax = atan[ΔW ÷ (n · D)]. The worked example and limits are below in plain text. Machine-readable: /ai/capabilities.json · /llms.txt
Measured along the mold-opening (pull) direction, from the parting line to the end of the face.
Minimum draft
Fills the base angle. Edit it if your resin supplier's guide says otherwise.
Typical depths only. The texture supplier's sheet lists the real depth of each pattern.
0.001 in = 0.0254 mm.
1.5 is the common texture-supplier rule; some fine patterns are rated near 1.0.
Leave blank to compute the geometry at the recommended angle.
Dimension check (optional)
Outside of a box: at the parting line. Boss or rib: at the base. Hole or pocket: at the opening.
For example, how much smaller the bottom of a housing may be than its top before a mating part, a label or a fixture stops fitting.

Engineering estimate, not a quote. Final draft angles are agreed with the toolmaker and texture supplier during the mold design review.

How this works

Draft is the small taper given to every face that runs parallel to the direction the mold opens. Without it, the part has to be dragged along the steel for the whole depth of the face while it is still warm and shrinking. With it, the face separates from the steel the moment the part starts to move. The calculator does two separate jobs: it estimates how much draft a face needs, and it works out what that draft does to the part's dimensions.

Step 1: minimum draft. Resin-supplier part design guides commonly give a base draft for smooth faces: about 1° per side as a general rule, as little as 0.5° on short, polished faces that the part shrinks away from, and more on faces the part shrinks onto. Texture adds to that. Mold-texturing suppliers publish a rule of thumb of about 1.5° of extra draft for every 0.001 in (0.0254 mm) of texture depth, and their sheets list a specific minimum for each pattern. This page adds the two and rounds up to the next 0.5° so the angle is easy to model and to machine.

Sources for the rules. The base angles and the core-side versus cavity-side guidance follow the draft chapter of R. A. Malloy, Plastic Part Design for Injection Molding (Hanser), and the part design guides published by the major resin suppliers. The texture allowance of about 1.5° per 0.001 in of texture depth is the rule of thumb published in mold-texturing suppliers' design guidelines (for example, Mold-Tech's). The dimensional part of the calculator is exact trigonometry and needs no source beyond the definition of the tangent.

Step 2: geometry. Once you have an angle, the rest is right-angle trigonometry. The face moves sideways by its depth times the tangent of the angle. A feature drafted on both sides changes width by twice that. Run it backwards and a tolerance tells you the largest angle you can afford.

Minimum draft θ_min = θ_base + k × (h_in ÷ 0.001) h_in = texture depth in inches (mm ÷ 25.4) Recommended draft θ_rec = θ_min rounded up to the next 0.5° Offset per side e = D × tan θ Width change ΔW = n × D × tan θ n = number of drafted sides (1 or 2) Narrow-end width W_narrow = W − n × D × tan θ Largest draft a tolerance allows θ_max = atan[ ΔW_allowed ÷ (n × D) ] Ejection travel before texture clears s = h ÷ sin θ Handy constant: 1° of draft ≈ 0.0175 per unit of depth (0.44 mm per 25 mm, 0.0175 in per inch)
Cross-section of a drafted part between core and cavity A cap-shaped molded part sits over a tapered core, with the cavity half above it and the parting line below. The mold opens upward. The outside faces of the part lean inward by the draft angle theta, measured from the pull direction. Over the draw depth D, each face moves sideways by D times tan theta, so the top of the part is narrower than the wide end at the parting line by twice that amount. The angle is exaggerated for clarity. cavity half core half (part shrinks onto it) molded part parting line pull θ ← e = D·tan θ (offset per side, over the full depth) draw depth D narrow end = W − 2·D·tan θ wide end W (at the parting line)
Figure 1. The draft angle θ is measured from the pull direction, not from the parting plane. Each drafted face moves sideways by D·tan θ over its depth, so a feature drafted on both sides is 2·D·tan θ narrower at one end. Inside and outside faces lean by the same angle here, so the wall keeps a constant thickness. Angle exaggerated for clarity.

Worked example

A handheld ABS housing has a 30 mm deep outside wall with a medium texture 0.002 in (0.0508 mm) deep. The housing is 80 mm wide at the parting line, and the mating cradle it slides into allows the bottom to be at most 3.0 mm narrower than the top.

Texture allowance k × (h_in ÷ 0.001) = 1.5 × (0.0508 ÷ 25.4 ÷ 0.001) = 1.5 × 2.0 = 3.0° Minimum draft θ_min = 1.0° base + 3.0° = 4.0° → recommended 4.0° Offset per side e = 30 × tan 4.0° = 30 × 0.06993 = 2.098 mm Width change ΔW = 2 × 2.098 = 4.196 mm Narrow end 80 − 4.196 = 75.804 mm Largest draft the cradle allows θ_max = atan[3.0 ÷ (2 × 30)] = atan 0.0500 = 2.862° Ejection travel before the texture clears 0.0508 ÷ sin 4.0° = 0.0508 ÷ 0.06976 = 0.728 mm Conflict: the texture needs 4.0°, the fit allows only 2.86°. Option A, light texture 0.001 in: θ_min = 1.0 + 1.5 = 2.5° → e = 30 × tan 2.5° = 1.310 mm, ΔW = 2.620 mm ≤ 3.0 ✔ Option B, keep the medium texture on the top 15 mm only, smooth 1° below: 15 × tan 4° + 15 × tan 1° = 1.049 + 0.262 = 1.311 mm per side, ΔW = 2.621 mm ≤ 3.0 ✔

This is the most common draft conflict on consumer housings: an industrial designer picks a texture, an engineer sets a fit, and nobody checks the two against each other until the texture shop asks for more draft after the steel is cut. Press Load the worked example above to see the calculator flag the conflict and reproduce these numbers.

Offset per side versus depth for common draft angles Line chart of sideways offset per drafted face in millimetres against face depth from 0 to 100 millimetres, for draft angles of 0.5, 1, 2, 3, 4 and 5 degrees. Each line is straight because offset equals depth times tan theta. At 100 mm depth the offsets are about 0.87, 1.75, 3.49, 5.24, 6.99 and 8.75 mm. The worked example, 30 mm deep at 4 degrees, is marked at 2.10 mm. 0246810 mm 020406080100 mm depth of the drafted face D (mm) offset per side (mm) 0.5°1°2°3°4°5° worked example: 30 mm at 4° → 2.10 mm 1° ≈ 0.0175 mm of offset per mm of depth; every line is straight
Figure 2. Sideways offset of one drafted face, drawn to scale (5.2 px per mm of depth, 24 px per mm of offset). A feature drafted on both sides changes width by twice the value read here. Deep faces turn a small angle into a large dimensional change, which is why deep boxes are where draft and tolerance collide.

Quick reference: offset per side

Drafttan θPer 25 mm of depthPer 1 in of depth
0.5°0.008730.218 mm0.0087 in
1°0.017460.436 mm0.0175 in
1.5°0.026190.655 mm0.0262 in
2°0.034920.873 mm0.0349 in
3°0.052411.310 mm0.0524 in
5°0.087492.187 mm0.0875 in

Why texture needs so much more draft

A texture is a field of tiny peaks and valleys etched or machined into the steel, and the plastic fills every one of them. Each valley in the part is locked around a peak in the steel, so a textured wall behaves like a surface covered in very small undercuts. On a zero-draft wall those peaks have to plough through the plastic for the full depth of the face, which leaves bright drag lines, polished streaks or torn grain. Draft solves this geometrically: as the part travels a distance s along the pull, the face lifts away from the steel by s · sin θ. Once that lift exceeds the texture depth h, the peaks are clear. The ejection travel spent scuffing is therefore about h ÷ sin θ. For a 0.0508 mm texture that is 0.73 mm at 4° but 2.9 mm at 1°, four times as much scraping. That is the physical reason behind the per-texture-depth rule.

Why textured walls need extra draft Two close-ups of a textured steel wall and the plastic molded against it. On the left, with no draft, the steel peaks stay locked in the plastic during ejection and drag along it, leaving scuff lines. On the right, with draft, the part lifts away from the wall by s times sin theta as it travels s along the pull, and the peaks clear once that lift is larger than the texture depth h. 0° draft: peaks drag the full depth With draft θ: peaks clear after s = h ÷ sin θ textured steel part: drag lines eject θ gap = s · sin θ clear when gap > h eject s textured steel part lifts away
Figure 3. Texture peaks behave like tiny undercuts. With no draft they scrape the part for the whole depth of the face. With draft the part lifts away by s · sin θ as it travels s, and the scuffing stops once that gap exceeds the texture depth h. Schematic, not to scale.

Common mistakes

When to use this calculator vs other methods

MethodUse it whenLimit
This calculatorSetting draft at concept stage, checking a texture against a fit, writing a general draft noteRules of thumb for the angle; the geometry is exact
Texture supplier's pattern sheetAny face with a named textureCovers texture only, not the fit or the core-side grip
CAD draft analysisFinding every face below the target angle on a near-final modelNeeds the right pull direction and target; says nothing about whether the target is right
Ejection-force calculation or simulationDeep cores, high-shrink resins, very low draft, thin-walled parts that may crack or bow on ejectionNeeds friction and shrinkage data that are often uncertain
Side action, collapsing core or stripper plateA face that must be straight or nearly soAdds mold complexity and maintenance; decide before the mold is designed

Design tips for draft

Questions and answers

How much draft angle does an injection molded part need?

A common starting rule is 1° of draft per side on smooth walls. Polished faces on the cavity side, which the part shrinks away from, can often release at about 0.5°. Faces on the core side, which the part shrinks onto, and deep draws usually need 1.5° to 2° or more. Textured faces need extra draft on top of that, commonly about 1.5° for every 0.001 in (0.0254 mm) of texture depth. Your texture supplier's sheet for the exact pattern overrides any general rule.

How much draft do I need for a textured surface?

Add roughly 1.5° of draft for every 0.001 in (0.0254 mm) of texture depth to the draft the smooth wall would need. For a 0.002 in (0.0508 mm) deep texture on a wall that would otherwise take 1°, that is 1 + 2 × 1.5 = 4°. The texture's peaks and valleys act like thousands of tiny undercuts; draft is what lifts the part away from them instead of dragging across them.

How do you calculate how much a draft angle changes a dimension?

The offset on one drafted face is the depth of the face times the tangent of the draft angle: offset = D × tan θ. One degree is about 0.0175 per unit of depth, so 1° over 25 mm moves the face about 0.44 mm. A feature drafted on both sides, such as a boss, a rib or the outside of a box, changes width by twice that: a 30 mm deep wall at 4° moves 2.098 mm per side and the width changes by 4.196 mm from end to end.

Which needs more draft, the core side or the cavity side?

The core side. Plastic shrinks as it cools, so it pulls away from the outer cavity walls but grips the core that forms its inside. That grip has to be overcome during ejection, so inside faces generally get more draft than outside faces of the same depth. A common pattern is 0.5° to 1° on a smooth outside face and 1° to 2° on the matching inside face.

Can a molded part have zero draft?

Sometimes, on short walls with highly polished steel, a low-friction resin and careful ejection, or where a side action, a collapsing core or a stripper plate moves the steel away from the face before the part is pushed. Zero draft usually means slower cycles, scuffing, higher ejection force, more mold maintenance or extra mold actions. If a face must be truly straight, call it out on the drawing and agree the method with the toolmaker before the tool is designed.

Where should a drafted dimension be measured?

The drawing has to say. A drafted face has a different size at each end, so a width, a hole diameter or a boss diameter needs a note stating whether it applies at the parting line, at the base, at the tip or at a stated height, and whether draft adds material or removes it. A common note is a general draft callout such as "draft 1° min unless otherwise specified", with critical features dimensioned at a named location.

Does draft change the wall thickness of a molded part?

Not if both faces of the wall are drafted by the same angle in the same direction; the wall stays a constant thickness and simply leans. It does change if only one face is drafted, or if the inside and outside use different angles. Then the wall tapers and gets thicker toward one end, which can cause sink and a longer cooling time at the thick end. Ribs are the exception by design: they are drafted on both faces so they narrow toward the tip.

Ask JCH about draft

Stuck between a texture your designer wants and a fit your engineer needs? Ask our AI assistant. It answers from this website, and our tooling team follows up if you want.

AI assistant. Answers can be wrong; nothing it says is a quote or a promise.

Want your draft checked before the steel is cut?

This calculator gives an engineering estimate. Our tooling team runs a draft and undercut review on your CAD, checks textured faces against your fits, and marks the faces that need more angle or a mold action while the change is still a CAD edit.

Book a 30-min call Send a drawing or sample