Answers › Molded threads

Should threads be molded into the plastic part or added later?

Reviewed by the JCH tooling team · Updated

Mold external threads whenever you can: split on the parting line, they cost almost nothing extra. Internal threads need an unscrewing core, a collapsible core or a stripped round thread, which adds moving steel and limits size. For standard screws or frequent service, a metal insert or a thread-forming screw is usually the better answer.

A thread can be molded into the part, formed later by a screw, carried by a metal insert, or machined after molding. The right choice depends on three things: which side of the part the thread is on, how often it will be turned, and how many parts you will make. External threads are cheap to mold. Internal threads are where the cost and the risk live.

The four routes compared

RouteWhat the mold needsGood forWatch out for
Molded external threadParting line through the thread axis, or an external unscrewing device if the axis runs with the mold openingCaps, bottle necks, knobs, large coarse threadsWitness line and possible flash along the thread; a slight mismatch at the split
Molded internal threadUnscrewing core, collapsible core, or a stripped round threadClosures and fittings made in volume that mate with your own partMoving steel, longer cycles, size limits
Thread-forming screw in a plain holeOnly a cored pinHousings opened a handful of timesWears out after a few reinstallations
Metal threaded insertA plain hole sized for the insert, or a locating pin if molded inFrequent service, standard machine screws, steady clamp loadsAn extra part and an extra step

External threads: split them on the parting line

DuPont and BASF give the same advice: put the parting line along the centerline of the thread so each mold half forms one side of it and opens away. It is the cheapest way to mold a thread, with no moving parts and no cycle-time penalty. Protolabs notes the split leaves a small undercut roughly 10° either side of the parting line on its milled molds, barely noticeable except on large or coarse threads; a flat-sided "half thread" design or cam-driven side actions remove it. If the thread axis has to point along the mold opening, the tool needs an external unscrewing device instead.

Internal threads: the core has to get out

An internal thread locks the part onto the core that formed it. DuPont lists three ways out: an automatic unscrewing device, a collapsible core, or a loose threaded insert loaded by hand and removed with the part. A fourth, stripping, works only for rounded threads in flexible parts.

Three ways a mold releases a thread: external thread split on the parting line, internal thread on a collapsible core, and a rounded internal thread stripped off a fixed core 1. External, on the parting line parting line on the axis: halves open sideways 2. Internal, collapsible core segments fold inward when the center pin pulls back 3. Internal, stripped stripper ring pushes the part over a fixed core; round thread, thin wall

Worked example: an acetal cap with an internal thread

A cap in acetal has an internal thread with a 22 mm major diameter and a 1.0 mm thread depth, and the deepest part of the thread sits 10 mm back from the core face. Can it come off a collapsible core, or could it simply be stripped?

Collapsible core check. DuPont's Delrin guide puts typical molding shrinkage at 1.8 to 2.2%; use 2.0%. DME's procedure subtracts shrinkage first: S = 22 × 0.020 = 0.44 mm. For its largest MiniCore the maximum major diameter is 24.51 − 0.44 = 24.07 mm, so 22 mm fits, and the minor diameter of 20 mm is above the 18.03 − 0.44 = 17.59 mm minimum. Available collapse falls by 0.02 mm for every millimeter back from the core face, and DME's table writes the usable undercut as 1.50 − (0.02 × L + 0.5 × S) = 1.50 − (0.20 + 0.22) = 1.08 mm. The 1.0 mm thread clears by 0.08 mm, with an interrupted thread. Make the thread 4 mm longer and the allowance drops to exactly 1.00 mm, with nothing to spare; at that point move to a standard core with full 360° threads or shorten the engagement.

Stripping check. With a 1.2 mm wall, 22 ÷ 1.2 is about 18, short of DuPont's 20-to-1 guide, and a sharp V thread can't strip anyway. Stripping would need a rounded thread and a wall near 1.1 mm. So this cap goes on a collapsible core or an unscrewing mold, and that choice is made before the tool is designed, since it sets the mold layout; see how injection molds are built and what drives mold cost. The plastic shrinkage calculator handles the shrink step for other resins.

CNC machining center milling a steel block, with the spindle, cutting tool and metal chips on the table
A CNC machining center cutting mold steel at a partner factory. Threaded cores, collapsible-core seats and unscrewing gear pockets are all machined like this, which is why internal threads add so much more to a mold than external ones.

Thread rules that apply to every molded thread

Plastic and metal threads together

If a plastic thread mates with metal, DuPont prefers the male thread on the plastic part, because plastic expands much more with heat and will creep or relax if it is stretched around a metal male over temperature swings. If the plastic must be the outer part, it may need a metal backup sleeve. BASF warns about tapered pipe threads in particular: the taper wedges the plastic outward, and an over-tightened fitting can split. Give it a positive stop, such as a shoulder at the bottom of the internal thread.

How to decide

  1. External thread you design both halves of? Mold it on the parting line.
  2. Internal thread, high volume, mating your own part? Mold it, and size it against the core maker's tables before the part design freezes.
  3. Internal thread that takes a standard machine screw, or will be serviced often? Use a threaded insert, molded in or installed after; for the molded-in option see insert molding.
  4. Screw that goes in once or twice? A plain cored hole and a thread-forming screw; see how to design screw bosses.
  5. Small quantity of a part that needs an internal thread? Protolabs suggests machining threads after molding can cost less than molding them at low volume.

Common questions

Can internal threads be injection molded?

Yes. The mold needs a way to release the core: an unscrewing mechanism that turns it out, a collapsible core whose segments fold inward, or a rounded thread on a thin wall that can be stripped off. Each adds cost or limits the thread, so many products use inserts or thread-forming screws instead.

How are external threads molded without a slide?

The parting line runs along the thread's axis, so each mold half forms one side and the halves open away from the thread. It leaves a small witness line and can cause slight flash or a minor undercut near the split, which matters only on large or coarse threads.

What is a collapsible core?

A segmented mold core that expands over a center pin to form an internal thread or undercut and then folds inward when the pin retracts, so the part can be pushed off. DME's standard cores cover outside diameters from about 18 to 107 mm; smaller versions give interrupted threads.

Can a threaded plastic part be stripped off the mold?

Only if the thread is rounded and the part can stretch. DuPont specifies a round thread with a radius of 0.288 times the pitch and, as a guide, a diameter at least 20 times the wall thickness, plus a resin that recovers well. Sharp V threads and thick walls cannot be stripped.

Is a molded thread as strong as a metal insert?

Usually not for repeated use. Plastic threads strip more easily than metal ones, especially fine pitches, and they creep under steady load. A molded thread is fine for caps and parts you design both halves of; for standard machine screws or frequent service, a brass or steel insert is more durable.

Sources

Send the part file and the quantity you expect to run, and we'll review it before you commit to tooling. NDA first if you want one.

Send a part for reviewBook a 30-minute call