Mold external threads whenever you can: split on the parting line, they cost almost nothing extra. Internal threads need an unscrewing core, a collapsible core or a stripped round thread, which adds moving steel and limits size. For standard screws or frequent service, a metal insert or a thread-forming screw is usually the better answer.
A thread can be molded into the part, formed later by a screw, carried by a metal insert, or machined after molding. The right choice depends on three things: which side of the part the thread is on, how often it will be turned, and how many parts you will make. External threads are cheap to mold. Internal threads are where the cost and the risk live.
| Route | What the mold needs | Good for | Watch out for |
|---|---|---|---|
| Molded external thread | Parting line through the thread axis, or an external unscrewing device if the axis runs with the mold opening | Caps, bottle necks, knobs, large coarse threads | Witness line and possible flash along the thread; a slight mismatch at the split |
| Molded internal thread | Unscrewing core, collapsible core, or a stripped round thread | Closures and fittings made in volume that mate with your own part | Moving steel, longer cycles, size limits |
| Thread-forming screw in a plain hole | Only a cored pin | Housings opened a handful of times | Wears out after a few reinstallations |
| Metal threaded insert | A plain hole sized for the insert, or a locating pin if molded in | Frequent service, standard machine screws, steady clamp loads | An extra part and an extra step |
DuPont and BASF give the same advice: put the parting line along the centerline of the thread so each mold half forms one side of it and opens away. It is the cheapest way to mold a thread, with no moving parts and no cycle-time penalty. Protolabs notes the split leaves a small undercut roughly 10° either side of the parting line on its milled molds, barely noticeable except on large or coarse threads; a flat-sided "half thread" design or cam-driven side actions remove it. If the thread axis has to point along the mold opening, the tool needs an external unscrewing device instead.
An internal thread locks the part onto the core that formed it. DuPont lists three ways out: an automatic unscrewing device, a collapsible core, or a loose threaded insert loaded by hand and removed with the part. A fourth, stripping, works only for rounded threads in flexible parts.
A cap in acetal has an internal thread with a 22 mm major diameter and a 1.0 mm thread depth, and the deepest part of the thread sits 10 mm back from the core face. Can it come off a collapsible core, or could it simply be stripped?
Collapsible core check. DuPont's Delrin guide puts typical molding shrinkage at 1.8 to 2.2%; use 2.0%. DME's procedure subtracts shrinkage first: S = 22 × 0.020 = 0.44 mm. For its largest MiniCore the maximum major diameter is 24.51 − 0.44 = 24.07 mm, so 22 mm fits, and the minor diameter of 20 mm is above the 18.03 − 0.44 = 17.59 mm minimum. Available collapse falls by 0.02 mm for every millimeter back from the core face, and DME's table writes the usable undercut as 1.50 − (0.02 × L + 0.5 × S) = 1.50 − (0.20 + 0.22) = 1.08 mm. The 1.0 mm thread clears by 0.08 mm, with an interrupted thread. Make the thread 4 mm longer and the allowance drops to exactly 1.00 mm, with nothing to spare; at that point move to a standard core with full 360° threads or shorten the engagement.
Stripping check. With a 1.2 mm wall, 22 ÷ 1.2 is about 18, short of DuPont's 20-to-1 guide, and a sharp V thread can't strip anyway. Stripping would need a rounded thread and a wall near 1.1 mm. So this cap goes on a collapsible core or an unscrewing mold, and that choice is made before the tool is designed, since it sets the mold layout; see how injection molds are built and what drives mold cost. The plastic shrinkage calculator handles the shrink step for other resins.

If a plastic thread mates with metal, DuPont prefers the male thread on the plastic part, because plastic expands much more with heat and will creep or relax if it is stretched around a metal male over temperature swings. If the plastic must be the outer part, it may need a metal backup sleeve. BASF warns about tapered pipe threads in particular: the taper wedges the plastic outward, and an over-tightened fitting can split. Give it a positive stop, such as a shoulder at the bottom of the internal thread.
Yes. The mold needs a way to release the core: an unscrewing mechanism that turns it out, a collapsible core whose segments fold inward, or a rounded thread on a thin wall that can be stripped off. Each adds cost or limits the thread, so many products use inserts or thread-forming screws instead.
The parting line runs along the thread's axis, so each mold half forms one side and the halves open away from the thread. It leaves a small witness line and can cause slight flash or a minor undercut near the split, which matters only on large or coarse threads.
A segmented mold core that expands over a center pin to form an internal thread or undercut and then folds inward when the pin retracts, so the part can be pushed off. DME's standard cores cover outside diameters from about 18 to 107 mm; smaller versions give interrupted threads.
Only if the thread is rounded and the part can stretch. DuPont specifies a round thread with a radius of 0.288 times the pitch and, as a guide, a diameter at least 20 times the wall thickness, plus a resin that recovers well. Sharp V threads and thick walls cannot be stripped.
Usually not for repeated use. Plastic threads strip more easily than metal ones, especially fine pitches, and they creep under steady load. A molded thread is fine for caps and parts you design both halves of; for standard machine screws or frequent service, a brass or steel insert is more durable.
Send the part file and the quantity you expect to run, and we'll review it before you commit to tooling. NDA first if you want one.
Send a part for reviewBook a 30-minute call